Cut Parameters tab, Engraving, 2½ Axis

<< Click to Display Table of Contents >>

Navigation:  MILL Module > Creating 2½ Axis Operations > Engraving >

Cut Parameters tab, Engraving, 2½ Axis

The following Cut Parameters tab allows you to define the cut parameters for the current 2½ Axis Engraving operation.  You can set Global Parameters, Location of Cut Geometry and Cut Depth Control via this tab of the operation dialog.  The Global Parameters section allows you to set the tolerance value to be used in machining.

 

tog_minusDialog Box: Cut Parameters tab
Dialog Box: 2½ Axis Engraving

Dialog Box: 2½ Axis Engraving
tog_minusGlobal Parameters
Global Parameters, 2½ Axis Engraving

Global Parameters, 2½ Axis V-Carving

The Global Parameters section allows you to set the tolerance value to be used in machining.

•Tolerance
This is the allowable deviation from the actual part geometry plus the Stock layer (if any).

How to Increase Tool Path AccuracyTolerances play a vital role in both design engineering and digital manufacturing.  In design, the goal is to allow the broadest tolerance range possible while meeting your design specifications. This is because, generally speaking, there is a direct correlation between tighter tolerances and higher manufacturing costs.

Read the full article...
tog_minusCut Direction

Select from the following for the engrave Cut Direction:

•Natural
Toolpath follows the same direction as the direction of curve geometry.

•Reversed
Toolpath follows the reverse (opposite) direction of curve geometry.
tog_minusLocation of Cut Geometry
Location of Cut Geometry, 2½ Axis V-Carving

Location of Cut Geometry, 2½ Axis V-Carving

The cutter can be set to cut inside the curve or trace the outside of the curve.  The Location of Cut Geometry can be set to At Top (top Z level), At Bottom (bottom Z level) or Pick Top (specifying the Z location) by entering a Z value location or by selecting the pick Pick button and selecting the point on the part.

At Top  

This uses the Z location of the selected Machining Features/Region as the top of cut. The generated cuts will start at this Z location and cut down in Z to the specified total cut depth.

At Bottom  

This uses the Z location of the selected Machining Features/Region as the bottom of cut. The generated cuts will be above the selected machining region and last cut would be at the Z location of the specified region.

Pick Top  

This allows you to specify the Top of Cut for the selected Machining Features/Region and is typically used when the selected region is not at top or bottom. The generated cuts will start at this specified Z location and cut down in Z to the specified total cut depth.
tog_minusCut Depth Control

The Cut Depth Control enables you to define the depth of the cut. You can define a Rough Depth and a Finish Depth by either typing in the desired values or by using the slider bars provided. Similarly you can define the Depth per Cut for both the Roughing and the Finishing paths.

Cut Depth from ToolSelect this icon to assign the Cut Depth value that is defined by the tool that is currently active for this operation. Note: This icon will ONLY appear in this dialog if the currently active tool has a Cut Depth value assigned to it.  Edit the tool definition if desired.
tog_minusCut Traversal between Cut Levels

This can be set to Zig or ZigZag. Setting the cut traversal to Zig generates cuts along the direction of the curve, retracts the tool to cut transfer plane and starts at the same start location for the next level. Setting the cut traversal to ZigZag cuts both directions.

Engrave, Zig

Engrave, Zig
Engrave, ZigZag

Engrave, ZigZag